COE-FORUM-USER
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| 21 Jan 2002 12:46 PM |
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Try this...Create a sketch that has multiple closed profiles. Select the Pad or Pocket feature and right click in the "Profile Selection" field. This will give you an option 'go to profile definition'. Select that option and select the closed profile of the multi-profile sketch that you want to create the feature from. Your feature is now related to only that portion of the sketch. Repeat for other closed profiles.
I did notice this in the documentation...try \cathlp1368.htm (I am using V5R5 Sp5.
Author: Allen J. Smith |
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COE-FORUM-USER
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| 07 Jan 2002 06:11 AM |
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Do the following:
Create a sketch to use as your master. Then copy the sketch. Now paste/special with link the sketch. Either into the same part or into another part within the same product. The pasted sketches are linked to the master. (Note: if you have done this properly, the linked sketches will either have a blue arrow on the symbol in the spec. tree or a green diamond. The blue arrow exists for a sketch linked within the same part, the green diamond exists for a sketch linked between two parts).
Now any changes you make to the master are updated into the linked copies. Once you have the linked sketches you can create separate pads for each sketch. I have aattched a sample product illustrating the concept.
Author: Brian Roach |
Attachment: Product1.CATProduct
Attachment: Part1.CATPart
Attachment: Part2.CATPart
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COE-FORUM-USER
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| 08 Jan 2002 03:00 AM |
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Alternatively without using the Copy & Paste Special command we can pick the same Master sketch again to create another part with different Height of Pad. This will maintain the associativity with the master sketch.
Hope this helps
Bye
Author: CatMan |
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COE-FORUM-USER
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| 15 Jan 2002 07:23 PM |
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Thanks Brian for your tip
We tried your method and have now managed to get
multiple Pads that use the same Sketch profile.
We have written an operating instruction so our
users can now correctly preform this task.
Too bad that the V5 online help and training material
does not cover this method (or any other method).
Why cann't we get some decent Docs on how to use V5.
Its not just knowing how to use the Functions but what
methods that you should use.
Regards Phil
Author: Phillip Murnain |
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COE-FORUM-USER
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| 17 Mar 2006 12:32 PM |
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| We're using the copy paste speical with link method here and we're having problems with the sketch losing it's link to the master sketch. Any suggestions? |
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COE-FORUM-USER
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| 17 Mar 2006 01:12 PM |
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Stickman, not sure the problem youre having havent had any issues with the copy / paste special...but if you are having problems you might want to try the suggestion Allen gave. I find it easier since there is no copying and pasting required and no possibility to lose links with the master since there is no master.
A clarification to his directions when you click on pad or pocket you need to make sure you dont have a sketch preselected or it will automatically enter in the sketch as the profile. Also to get to "go to profile definition" you need to right click in the text box that indicates the profile/surface you are using (it should say no selection at the time). You can then click on the portion of the sketch you want to use.
Also new to R14 they added a feature called "profile feature" that is in the tools toolbar when within a sketch. Select the button and click on closed profile. Now when you exit the sketch you will find a child under the sketch called output that will list outputs of the profiles you created. You can use these profiles to create the pads and pockets. Not sure if this is better or worse than doing the profile definition...
Not really an answer to question but I thought I would throw it out there...
Elijah
(V5 R14) |
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DavidSiebenaler
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| 17 Mar 2006 01:20 PM |
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Using sketches as external parents can be troublesome and there are a couple of “happy paths.
In older released, when using an external sketch I’ve found it works best to first copy with link the sketch into your part and then use this sketch to create features in the child part. Depending on what release you are using this link can behave differently than selecting the external sketch while generating the feature in the child part.
An even better method is to create sketch profiles and/or outputs; publish the profiles and/or outputs; and then use these in the child parts. Using profiles and outputs as external references limits the impact of changes to the sketch to only the elements actually modified.
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David M. Siebenaler
The Boeing Company
Phantom Works |
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COE-FORUM-USER
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| 20 Mar 2006 04:24 AM |
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Stickman,
I'm not sure if this is what you mean, but I have found that opening a part with a link to a sketch or body using "Paste Special -> As Result with Link", sometime the parent part is not loaded and a red dot is shown.
Right clicking the item in the tree and choosing something like "load", or better yet entering Desk, right clicking the parent part and choosing "Load" sorts it out. Usually the part you are interested will require an update, but then all should be well.
Good luck
Jonathan |
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