Detail and Quick Detail views in Drafting

COE Administrator

Detail and Quick Detail views in Drafting
Does anyone help me about the differences between Detail and Quick Detail views in Drafting module. I couldn't find difference. Thanks everybody

COE Administrator

Detail and Quick Detail views in Drafting
(in response to COE Administrator)
The boundary is entirely enclosed in a quick detail. Other than that, I don't really know of anything different.

COE Administrator

Detail and Quick Detail views in Drafting
(in response to COE Administrator)
I might say something stupid (again?) but I think quick Detail is based on the reference view only, while detail is link to the 3D (and ref view also). This is why Detail view make border line only in the solid.

but I might be wrong...

COE Administrator

Detail and Quick Detail views in Drafting
(in response to COE Administrator)
Hi Eric!!!
You are perfectly Correct!!!

COE Administrator

Detail and Quick Detail views in Drafting
(in response to COE Administrator)
Hi Eric,

so what does "detail view based on the reference view" mean? is it about update relationship or something else?sorry but can u explain?

Thanks everybodyy

COE Administrator

Detail and Quick Detail views in Drafting
(in response to COE Administrator)
This is from the R14 online doc :
Quote


This task will show you how to create from the 3D a detail view using either a circle as callout or a sketched profile. Note that the procedure varies slightly depending on the method you choose.
A detail view is a partial generated view that shows only what is necessary in the clear description of the object. Note that the Detail view command uses a Boolean operator from the 3D whereas the Quick Detail view command computes the view directly from the 2D projection. The representation is therefore different.



What it means...hmmm...


hmmm...


well.....

COE Administrator

Detail and Quick Detail views in Drafting
(in response to COE Administrator)
Basically, it means that the Quick detail view looks at the 2D geometry created in the view. The standard Detail view goes back to the 3D geometry to extract the information.

For fun, create a view of a part. Then in the drafting area, delete an element, or elements. This will create a modified drafted view. In that area, create a quick detail view. Notice the quick detail view will contain only the geometry that is available in the drafted area. This means that any 2D geometry deleted will not be created in the quick detail view. Inversely, if you create additional geometry, it should also appear in the quick detail view. Now, create a standard detail view. Notice the geometry that you erased from the view will now re-appear. This is because the standard detail view looks back at the 3D geometry to extract the 2D geometry.

- Brian
---------------
Brian Brown
WSU CAD/CAM Laboratory
"CATIA Education at its best!"
[login to unmask email]

COE Administrator

Detail and Quick Detail views in Drafting
(in response to COE Administrator)
Thank u very much for your explanation Brian. Now it is clear for me.

COE Administrator

Detail and Quick Detail views in Drafting
(in response to COE Administrator)
Quote

Inversely, if you create additional geometry, it should also appear in the quick detail view


this does not work for me with R14 SP4 HF4

also try this :

create a pad, make front view and 2 detail views on corners(quick and normal detail),
go to the pad and make some fillet or chanfer
do not update front view but only detail views... both will show the fillet or the chanfer even the quick detail view based on the non updated (no fillet or chanfer) front view...

So the quick detail view is not only link to the front view geometry but also to the 3D...

COE Administrator

Detail and Quick Detail views in Drafting
(in response to COE Administrator)
Brian, its about time you showed your face here. Teach us newbs know how to do it, but be gentle.