Hello All,
Is there any way to export some dxf file with specified origin? As of now Catia saves sheet origin(lower left corner) as dxf origin.
Or can I move my view on the lower left corner of sheet by aligning its origin to that corner with exact precision?
Thanks
Hi all,
I have this same requirement. I looked at the help View Positioning - Set Relative Position, thanks to Samarinder's hint.
I can get the black do to blink red, and move things around, but see no way other the “eye ball”…. Just a visual line up. It there a way to just type in X0 Y0, or a contextual selection somewhere to snap the view to the lower right hand corner?
Thanks
Dave
Dave Frank * Bell Helicopter * Grand Prairie Texas
Advanced Computer Aided Manufacturing Systems Engineer
COE Product Co-Chairman, Digital Numerical Control
Hi Dave,
Here is the macro and it works fine in R22 sp4.
'Module1_Move_ViewOrigin
Sub CATMain()
Dim drawingDocument1 As DrawingDocument
Set drawingDocument1 = CATIA.ActiveDocument
Dim drawingSheets1 As DrawingSheets
Set drawingSheets1 = drawingDocument1.Sheets
Dim drawingSheet1 As DrawingSheet
Set drawingSheet1 = drawingSheets1.Item("Sheet.1")
Dim drawingViews1 As DrawingViews
Set drawingViews1 = drawingSheet1.Views
Dim drawingView1 As DrawingView
Set drawingView1 = drawingViews1.Item("Front view")
drawingView1.Activate
drawingView1.xAxisData = 0#
drawingView1.yAxisData = 0#
End Sub
